Broken-Out command

You create a broken-out section view by drawing a closed profile on a source drawing view (A), defining the depth of the broken-out portion (B), and then specifying the drawing view you want to break away (C). The profile can consist of any 2D elements, such as lines, arcs, and B-spline curves.

When you finish the command, the broken-out portion is displayed and the profile is hidden (D).

You also can specify that the drawing view to be broken out is different than the drawing view on which the profile is drawn. For example, you can draw the profile on a principal view (A), and then specify that a pictorial view is broken out (B). The broken-out section is applied perpendicular to the plane of the source view.

You can define the extent depth of the cut using any of these methods.

• By typing a value in the Depth box on the command bar.

• By clicking in free space.

• By clicking a keypoint or a centerline in a drawing view that is folded 90 degrees from the source view where the profile is drawn.

  Note:

  This method defines an associative extent depth that updates when the model changes.

You can modify a broken-out section view by modifying the profile or extent depth used to create it. To make the profile accessible, you must first select the Show Broken-Out Section view profiles option on the General tab (Drawing View Properties dialog box).

For more information, see Modify a broken-out section view.

You can control the line style used to display the hatch boundary edges in a broken-out section view using the Annotation page (Drawing View Properties dialog box).

• Use the Show boundary edges check box to display the hatch boundary as a thin line. When deselected, the Visible edge style setting on the Display page (Drawing View Properties dialog box) controls edge display. Often, this is a thicker line.

• Use the Boundary edges style list to choose the line style to apply.

This line style control is available for broken-out section views that are created using the same drawing view to draw the profile and to apply the section. You can touch up the hatch boundary edges using the Edge Painter, Show Edges, and Hide Edges commands.